Integrated BIM tools, including Revit, AutoCAD, and Civil 3D
Professional CAD/CAM tools built on Inventor and AutoCAD
Any referenced datasets can be downloaded from "Module downloads" in the module overview.
Transcript
00:02
Tool library set up in Fusion 360.
00:07
After completing this video, you'll be able to
00:09
identify tool, geometry and holder requirements. Create a new tool, library,
00:14
copy and edit library tools,
00:16
create a new end mill and define tool parameters for feeds and speeds.
00:22
Before we get into setting up our tool library and fusion 3 60.
00:26
I think it's important that we take a look
00:28
at the physical tools to better understand tool,
00:30
geometry and holder requirements.
00:33
As there are many different types of tools and holders on the market,
00:37
it's important that we understand what our machine requirements are and
00:40
what tools and holders are available to us in our shop.
00:44
So let's go ahead and hop into the shop and take a look at tools and holders
00:54
now that we have a good idea about tools and holders in their physical requirements.
00:59
Let's go ahead and take a look at how we can set this up digitally in fusion 360.
01:04
Now, it's not required that we have a design open.
01:06
So I'm gonna close our caliper design showing that we have an untitled document
01:11
because all of our tool data is going to be saved independent of our design.
01:15
We're gonna begin by navigating from the design workspace to manufacture
01:20
and then I'm gonna first change the units.
01:22
In
01:22
this case, we're gonna use inch units
01:25
while once again, that's not a strict requirement.
01:28
It does help to make sure that we identify the units that we want to
01:31
use in our design as it will have an effect on our tool library.
01:36
Then we're gonna navigate to manage and select tool library.
01:40
Now it's important to note that there are a couple
01:42
of different places that we can save tool libraries.
01:44
In fusion 3 60
01:46
we have a dedicated fusion 3 60 library that's gonna have some sample tools for us.
01:52
Things that we can grab copy, paste and modify as needed.
01:56
We also have a local library which will be saved on your local machine
01:60
and then we have a cloud library.
02:02
Also note at the very bottom that we have an option to download vendor libraries.
02:07
This could be extremely helpful as you can access
02:09
tools that have already been set up by tools.
02:11
In
02:12
this case, we want to take a look at the basic process.
02:16
I do want to note that if you do not see cloud available in your tool library,
02:20
you can go to your user preferences.
02:22
After we close the tool library,
02:24
go up to your user preferences,
02:26
make sure that we navigate to the manufacture workspace and enable cloud library.
02:32
Once we have that set up. We can go back into our tool library and we can take a look
02:37
at the very top. We have documents and untitled.
02:40
This is where any tools used inside of a specific part will be accessed
02:45
for our purposes.
02:46
We're gonna store our new library on the cloud, but you can do it locally as well
02:52
when we open up our cloud section.
02:54
If you've never created a tool library before,
02:57
you're not going to see anything here.
02:59
In order to create your own tool library,
03:01
we can right click on cloud and select new library.
03:05
Ultimately, what we're gonna be doing is importing a tool library,
03:08
but it's important that we understand how to set it up for ourselves.
03:12
So I'm gonna simply call this sample library because we aren't going to be using it.
03:18
Once we have our sample library in place,
03:21
there are two main ways that we can get tools and holders into our library.
03:25
One way is to create them new from scratch and
03:27
the other way is to copy them from another library.
03:30
First, let's take a look at copying them from the fusion 3 60 library.
03:35
We're gonna go into cutting tools inch
03:38
and notice.
03:38
Currently it says the selected library is turned off fusion 3 60 changes,
03:44
the opacity.
03:45
In this case, this library is shown in gray
03:47
and we need to enable it or turn it on.
03:50
This is specifically done.
03:52
So that way we don't have to load all the tools into our program.
03:56
Once we have this set up, we wanna make sure that we go to our milling section.
04:01
We want to select our Fusion 3 60 library and we're gonna turn all libraries on.
04:06
This is gonna bring everything in from the fusion 3 60 sample.
04:10
Next, we're gonna filter by milling
04:13
flat and mill and you can see everything here is sorted by inch or metric units.
04:19
We're gonna take a look at a half inch flat end
04:21
MLL and then we're going to right click and select copy tool
04:25
from here.
04:26
We want to go into our sample library in the cloud, right click and paste the tool.
04:31
When we paste this tool, it's important to note that the filters are still active.
04:36
So let's make sure that we do clear all of our filters
04:39
in the tool library.
04:40
We have an info section which will give
04:42
us information about the tool specifically its description,
04:46
vendor product ID and a link if one is
04:48
available and then general parameters about the tool.
04:51
And if we scroll down, we can see feeds and speeds
04:54
at the bottom center, we also have cutting data presets.
04:58
And you can see that for cutting data,
04:60
we have a default preset and below that we have ones for aluminum slotting,
05:04
roughing and finishing.
05:06
For example,
05:07
these are gonna be helpful as it changes things like
05:10
the lead in and lead out the feed per tooth.
05:12
The cutting feed rate surface speed and the R PM.
05:16
These can all be customized individually when we're
05:19
talking about adding them to a tool path.
05:21
But it is important that we get a good
05:22
baseline when we're setting up our tool library.
05:25
If you want to make any changes, you can right, click on the tool and select edit tool
05:30
from here. We can make adjustments to the general properties
05:34
specifics on the cutting.
05:35
For example, if we have a four flute tool that has a specific coating,
05:39
we can set that up here.
05:41
We can also modify how far the tool sticks out
05:44
below the holder by modifying things like length below holder.
05:48
There's information for cutting data to modify our feeds and speeds.
05:52
But once again note that these will be stored in cutting data presets.
05:55
So if you want to modify things like aluminum roughing,
05:58
make sure you preselect that cutting data.
06:01
And finally,
06:02
we have a post process tab which will determine things like the tool number.
06:05
This is an important aspect as we want to make
06:08
sure it matches the tool number inside of our tool crib
06:11
and that it automatically updates the length and diameter offset values.
06:15
Those will be extremely important as we get down
06:18
the line and modify things like cut or compensation.
06:21
We're going to accept this tool and then we're gonna take a look
06:23
at a way that we can create our own tool from scratch.
06:26
And then ultimately import a library
06:29
to create our own tool from scratch.
06:30
We want to make sure that we're in the library where we
06:32
want that tool to be contained and then select the plus icon.
06:37
Once we select plus, we'll have to determine what type of tool we're creating.
06:41
This can be everything from a blank holder, a probe,
06:44
cutting options for things like water jets and laser cutters.
06:48
We have turning tools and then we have hole making and milling tools.
06:52
Let's go ahead and create a flat end mill.
06:55
Once we do that, we can enter information, for example, the description
06:59
and we're gonna call this a 0.25 flat end mill, just a generic name.
07:06
Then we can go into our cutting data and modify the parameters.
07:10
In this case, we want to make sure that the diameter is 0.25.
07:13
We're gonna tab to the shaft diameter
07:15
which automatically updates to the tool diameter
07:18
tab to the overall length. In this case, we'll set it at 2.5 inches
07:22
length below holder will set to two
07:24
our shoulder length inch and a quarter
07:26
and our flute length will be three quarters of an inch.
07:29
This data should come directly from a tool manufacturer.
07:33
If you're buying a tool off the shelf,
07:34
you need to make sure that your digital tool matches the physical tool.
07:39
In this case, the tool doesn't currently have a holder. If we select holder,
07:43
we can pick from a default holder located in any of our libraries.
07:47
You'll notice at the very bottom we have holder inch.
07:50
And if we drop that down, you can see that it shows us BT and CT 40
07:56
we can select generic holders
07:58
as we go down the line. We wanna make sure that the holder does fit the diameter.
08:02
In this case, we're going to use AC T 40.25 by 1 38.
08:07
And we'll select that holder.
08:09
When we do that, you can see it's placed inside of our design.
08:13
We would then want to make sure that we go back to the
08:15
cutting section and make sure that the tool is extended below the holder,
08:20
the correct amount.
08:21
In this case, I'm gonna set it at one inch
08:24
and make some adjustments, the shoulder length set that at one inch as well.
08:28
So now you can see it modifies the tool's position in the holder.
08:32
This is important for us for collision
08:34
checking to ensure that the non cutting portion
08:36
of the tool and the holder did not intersect our stock or any work holdings.
08:41
And finally make sure that we do adjust the tool number length offset
08:44
and diameter to make sure that those are all correct for our uses.
08:48
Once we accept that, now the tool will be stored inside of our library.
08:53
Once again, we need to make sure that our feeds and speeds are correct.
08:56
And this is general information that will come from the tool manufacturer and
08:60
then you can validate it and prove it out through sample programs.
09:03
But now let's talk about how to import a tool library
09:07
from here. I'm going to go to my cloud option.
09:09
Right, click and select import libraries.
09:12
Navigate to the location where you save the precision machine and caliber dash host
09:16
dot tools file and select open.
09:19
This is going to place this tool library in your cloud or local library.
09:23
Wherever it was imported to
09:25
this library contains ac
09:33
All the tools in this list.
09:34
With the exception of the drills have hot links directly to the
09:37
website.
09:39
When you set up your own tool library,
09:41
make sure that you are using tools that you do have available at your shop.
09:45
For example, in this tool list, tool number one is a 90 degree spot drill.
09:49
But in reality,
09:50
if you're using 100 and 18 degree job or drill bits for tool three and tool four,
09:55
you would want to make sure that you do have
09:57
a spot drill that has 100 and 20 degree angle.
10:00
So these are things that are not going to be set up
10:03
for you because every shop has different tools available to them.
10:06
If you want to go through the host tooling website,
10:09
you can take a look at the product links for the various tools.
10:12
Again, with the exception of the drill bits,
10:14
these are standard drill bits that have come from the fusion 3 60 library.
10:18
If you follow the product links, you can go to the
10:20
website and navigate to feeds and speeds information provided by ho
10:25
what we have here is the max spindle speed set on all the tools at 8100 R PM,
10:30
which is the max spindle speed.
10:32
On a HO
10:32
VF two,
10:34
you can obviously adjust these values based on your requirements,
10:37
but everything has been currently set with a HO
10:39
VF two max limit.
10:42
You can see that this tool list contains information for spot drill,
10:45
a champ for mill,
10:47
a handful of drill bits,
10:48
a quarter inch flat end mill, a shell mill for facing.
10:52
And then we have a flat end mill that we're using for roughing and finishing
10:55
a bull nose mill and followed up by a quarter 20 tap.
11:00
All this information will be used throughout our course,
11:02
but make sure that you do go into each tool, review the information
11:06
and navigate to the host website to identify the
11:08
tool and the feeds and speeds from them.
11:11
For now, let's go ahead and close this and because this is saved in the cloud,
11:14
nothing has to happen with our design, we can go ahead and move on to the next step.
Video transcript
00:02
Tool library set up in Fusion 360.
00:07
After completing this video, you'll be able to
00:09
identify tool, geometry and holder requirements. Create a new tool, library,
00:14
copy and edit library tools,
00:16
create a new end mill and define tool parameters for feeds and speeds.
00:22
Before we get into setting up our tool library and fusion 3 60.
00:26
I think it's important that we take a look
00:28
at the physical tools to better understand tool,
00:30
geometry and holder requirements.
00:33
As there are many different types of tools and holders on the market,
00:37
it's important that we understand what our machine requirements are and
00:40
what tools and holders are available to us in our shop.
00:44
So let's go ahead and hop into the shop and take a look at tools and holders
00:54
now that we have a good idea about tools and holders in their physical requirements.
00:59
Let's go ahead and take a look at how we can set this up digitally in fusion 360.
01:04
Now, it's not required that we have a design open.
01:06
So I'm gonna close our caliper design showing that we have an untitled document
01:11
because all of our tool data is going to be saved independent of our design.
01:15
We're gonna begin by navigating from the design workspace to manufacture
01:20
and then I'm gonna first change the units.
01:22
In
01:22
this case, we're gonna use inch units
01:25
while once again, that's not a strict requirement.
01:28
It does help to make sure that we identify the units that we want to
01:31
use in our design as it will have an effect on our tool library.
01:36
Then we're gonna navigate to manage and select tool library.
01:40
Now it's important to note that there are a couple
01:42
of different places that we can save tool libraries.
01:44
In fusion 3 60
01:46
we have a dedicated fusion 3 60 library that's gonna have some sample tools for us.
01:52
Things that we can grab copy, paste and modify as needed.
01:56
We also have a local library which will be saved on your local machine
01:60
and then we have a cloud library.
02:02
Also note at the very bottom that we have an option to download vendor libraries.
02:07
This could be extremely helpful as you can access
02:09
tools that have already been set up by tools.
02:11
In
02:12
this case, we want to take a look at the basic process.
02:16
I do want to note that if you do not see cloud available in your tool library,
02:20
you can go to your user preferences.
02:22
After we close the tool library,
02:24
go up to your user preferences,
02:26
make sure that we navigate to the manufacture workspace and enable cloud library.
02:32
Once we have that set up. We can go back into our tool library and we can take a look
02:37
at the very top. We have documents and untitled.
02:40
This is where any tools used inside of a specific part will be accessed
02:45
for our purposes.
02:46
We're gonna store our new library on the cloud, but you can do it locally as well
02:52
when we open up our cloud section.
02:54
If you've never created a tool library before,
02:57
you're not going to see anything here.
02:59
In order to create your own tool library,
03:01
we can right click on cloud and select new library.
03:05
Ultimately, what we're gonna be doing is importing a tool library,
03:08
but it's important that we understand how to set it up for ourselves.
03:12
So I'm gonna simply call this sample library because we aren't going to be using it.
03:18
Once we have our sample library in place,
03:21
there are two main ways that we can get tools and holders into our library.
03:25
One way is to create them new from scratch and
03:27
the other way is to copy them from another library.
03:30
First, let's take a look at copying them from the fusion 3 60 library.
03:35
We're gonna go into cutting tools inch
03:38
and notice.
03:38
Currently it says the selected library is turned off fusion 3 60 changes,
03:44
the opacity.
03:45
In this case, this library is shown in gray
03:47
and we need to enable it or turn it on.
03:50
This is specifically done.
03:52
So that way we don't have to load all the tools into our program.
03:56
Once we have this set up, we wanna make sure that we go to our milling section.
04:01
We want to select our Fusion 3 60 library and we're gonna turn all libraries on.
04:06
This is gonna bring everything in from the fusion 3 60 sample.
04:10
Next, we're gonna filter by milling
04:13
flat and mill and you can see everything here is sorted by inch or metric units.
04:19
We're gonna take a look at a half inch flat end
04:21
MLL and then we're going to right click and select copy tool
04:25
from here.
04:26
We want to go into our sample library in the cloud, right click and paste the tool.
04:31
When we paste this tool, it's important to note that the filters are still active.
04:36
So let's make sure that we do clear all of our filters
04:39
in the tool library.
04:40
We have an info section which will give
04:42
us information about the tool specifically its description,
04:46
vendor product ID and a link if one is
04:48
available and then general parameters about the tool.
04:51
And if we scroll down, we can see feeds and speeds
04:54
at the bottom center, we also have cutting data presets.
04:58
And you can see that for cutting data,
04:60
we have a default preset and below that we have ones for aluminum slotting,
05:04
roughing and finishing.
05:06
For example,
05:07
these are gonna be helpful as it changes things like
05:10
the lead in and lead out the feed per tooth.
05:12
The cutting feed rate surface speed and the R PM.
05:16
These can all be customized individually when we're
05:19
talking about adding them to a tool path.
05:21
But it is important that we get a good
05:22
baseline when we're setting up our tool library.
05:25
If you want to make any changes, you can right, click on the tool and select edit tool
05:30
from here. We can make adjustments to the general properties
05:34
specifics on the cutting.
05:35
For example, if we have a four flute tool that has a specific coating,
05:39
we can set that up here.
05:41
We can also modify how far the tool sticks out
05:44
below the holder by modifying things like length below holder.
05:48
There's information for cutting data to modify our feeds and speeds.
05:52
But once again note that these will be stored in cutting data presets.
05:55
So if you want to modify things like aluminum roughing,
05:58
make sure you preselect that cutting data.
06:01
And finally,
06:02
we have a post process tab which will determine things like the tool number.
06:05
This is an important aspect as we want to make
06:08
sure it matches the tool number inside of our tool crib
06:11
and that it automatically updates the length and diameter offset values.
06:15
Those will be extremely important as we get down
06:18
the line and modify things like cut or compensation.
06:21
We're going to accept this tool and then we're gonna take a look
06:23
at a way that we can create our own tool from scratch.
06:26
And then ultimately import a library
06:29
to create our own tool from scratch.
06:30
We want to make sure that we're in the library where we
06:32
want that tool to be contained and then select the plus icon.
06:37
Once we select plus, we'll have to determine what type of tool we're creating.
06:41
This can be everything from a blank holder, a probe,
06:44
cutting options for things like water jets and laser cutters.
06:48
We have turning tools and then we have hole making and milling tools.
06:52
Let's go ahead and create a flat end mill.
06:55
Once we do that, we can enter information, for example, the description
06:59
and we're gonna call this a 0.25 flat end mill, just a generic name.
07:06
Then we can go into our cutting data and modify the parameters.
07:10
In this case, we want to make sure that the diameter is 0.25.
07:13
We're gonna tab to the shaft diameter
07:15
which automatically updates to the tool diameter
07:18
tab to the overall length. In this case, we'll set it at 2.5 inches
07:22
length below holder will set to two
07:24
our shoulder length inch and a quarter
07:26
and our flute length will be three quarters of an inch.
07:29
This data should come directly from a tool manufacturer.
07:33
If you're buying a tool off the shelf,
07:34
you need to make sure that your digital tool matches the physical tool.
07:39
In this case, the tool doesn't currently have a holder. If we select holder,
07:43
we can pick from a default holder located in any of our libraries.
07:47
You'll notice at the very bottom we have holder inch.
07:50
And if we drop that down, you can see that it shows us BT and CT 40
07:56
we can select generic holders
07:58
as we go down the line. We wanna make sure that the holder does fit the diameter.
08:02
In this case, we're going to use AC T 40.25 by 1 38.
08:07
And we'll select that holder.
08:09
When we do that, you can see it's placed inside of our design.
08:13
We would then want to make sure that we go back to the
08:15
cutting section and make sure that the tool is extended below the holder,
08:20
the correct amount.
08:21
In this case, I'm gonna set it at one inch
08:24
and make some adjustments, the shoulder length set that at one inch as well.
08:28
So now you can see it modifies the tool's position in the holder.
08:32
This is important for us for collision
08:34
checking to ensure that the non cutting portion
08:36
of the tool and the holder did not intersect our stock or any work holdings.
08:41
And finally make sure that we do adjust the tool number length offset
08:44
and diameter to make sure that those are all correct for our uses.
08:48
Once we accept that, now the tool will be stored inside of our library.
08:53
Once again, we need to make sure that our feeds and speeds are correct.
08:56
And this is general information that will come from the tool manufacturer and
08:60
then you can validate it and prove it out through sample programs.
09:03
But now let's talk about how to import a tool library
09:07
from here. I'm going to go to my cloud option.
09:09
Right, click and select import libraries.
09:12
Navigate to the location where you save the precision machine and caliber dash host
09:16
dot tools file and select open.
09:19
This is going to place this tool library in your cloud or local library.
09:23
Wherever it was imported to
09:25
this library contains ac
09:33
All the tools in this list.
09:34
With the exception of the drills have hot links directly to the
09:37
website.
09:39
When you set up your own tool library,
09:41
make sure that you are using tools that you do have available at your shop.
09:45
For example, in this tool list, tool number one is a 90 degree spot drill.
09:49
But in reality,
09:50
if you're using 100 and 18 degree job or drill bits for tool three and tool four,
09:55
you would want to make sure that you do have
09:57
a spot drill that has 100 and 20 degree angle.
10:00
So these are things that are not going to be set up
10:03
for you because every shop has different tools available to them.
10:06
If you want to go through the host tooling website,
10:09
you can take a look at the product links for the various tools.
10:12
Again, with the exception of the drill bits,
10:14
these are standard drill bits that have come from the fusion 3 60 library.
10:18
If you follow the product links, you can go to the
10:20
website and navigate to feeds and speeds information provided by ho
10:25
what we have here is the max spindle speed set on all the tools at 8100 R PM,
10:30
which is the max spindle speed.
10:32
On a HO
10:32
VF two,
10:34
you can obviously adjust these values based on your requirements,
10:37
but everything has been currently set with a HO
10:39
VF two max limit.
10:42
You can see that this tool list contains information for spot drill,
10:45
a champ for mill,
10:47
a handful of drill bits,
10:48
a quarter inch flat end mill, a shell mill for facing.
10:52
And then we have a flat end mill that we're using for roughing and finishing
10:55
a bull nose mill and followed up by a quarter 20 tap.
11:00
All this information will be used throughout our course,
11:02
but make sure that you do go into each tool, review the information
11:06
and navigate to the host website to identify the
11:08
tool and the feeds and speeds from them.
11:11
For now, let's go ahead and close this and because this is saved in the cloud,
11:14
nothing has to happen with our design, we can go ahead and move on to the next step.
After completing this course, you’ll be able to:
Step-by-step guide
How to buy
Privacy | Do not sell or share my personal information | Cookie preferences | Report noncompliance | Terms of use | Legal | © 2025 Autodesk Inc. All rights reserved
Sign in to start learning
Sign in for unlimited free access to all learning content.Save your progress
Take assessments
Receive personalized recommendations
May we collect and use your data?
Learn more about the Third Party Services we use and our Privacy Statement. May we collect and use your data to tailor your experience?
Explore the benefits of a customized experience by managing your privacy settings for this site or visit our Privacy Statement to learn more about your options.