Integrated BIM tools, including Revit, AutoCAD, and Civil 3D
Professional CAD/CAM tools built on Inventor and AutoCAD
Any referenced datasets can be downloaded from "Module downloads" in the module overview.
Transcript
00:02
create and manage a digital tool library.
00:05
After completing this video, you'll be able to create a digital tool library,
00:09
create a custom digital tool,
00:11
copy and modify a digital tool and define tool parameters.
00:18
Infusion 3 60. We're going to get started with a new untitled document.
00:22
We're going to move to the manufacturer workspace.
00:25
And the first thing that I want to do is change the units in this case.
00:28
What we're going to be doing is we're going to be creating a tool library.
00:31
Infusion 3 60. The tool library is going to be independent of any document.
00:35
So changing the units here isn't really needed.
00:38
However,
00:39
it will affect the units that we see displayed
00:41
at the very basic level in our tool library.
00:44
Note that inside of our tool library there's going to be an all section
00:48
will be documents which will be tools that are used in your current document.
00:51
If you have multiple setups,
00:53
you'll also see them listed here underneath your untitled document.
00:57
We have a cloud library, a local library, the fusion 3 60 samples.
01:01
And at the very bottom we can download vendor libraries.
01:04
It's important to note that if you right click on the library,
01:08
you have the ability to turn the libraries on and off.
01:11
This can be done for individual samples.
01:14
For example, if you're not using any of the metric holders,
01:17
you can right click and you can turn this library off.
01:20
This means that it won't be displayed when you're taking a look at the
01:23
various tools and filtering through the different
01:26
holders inside of the sample library.
01:28
If you want to bring it back, you can always right click and turn that library on.
01:32
We're not going to be going through our vendor libraries in this case,
01:35
but I do think that it's important to explore what tools you
01:38
can download from vendor libraries without having to set them up manually.
01:42
Also note that if you don't see cloud listed inside of your tool library,
01:46
make sure that you go to your user preferences and
01:49
we want to make sure that we do enable them
01:51
from the general section you want to go to manufacture
01:53
and make sure that enable cloud libraries is checked.
01:57
Now let's go back into our tool library and let's take
01:60
a look at how we can create our own library.
02:02
All the tools inside of the fusion 3 60 sample library are read only.
02:07
This means that we can take a look at them and we
02:08
can use them in the current document but we can't modify them.
02:12
What we can do is we can create a library in either our local or our cloud location.
02:17
If you happen to log into fusion 360 from multiple computers.
02:20
It's a good idea that you do use the cloud location.
02:23
There are other places in which you can save
02:25
two libraries as well as post processor data by using
02:28
the assets inside of the data panel but we're going
02:31
to focus solely on the cloud and local libraries.
02:34
We're gonna right click and we can either create
02:36
a new empty library that we want to populate.
02:39
We can create a new folder inside of our cloud library or we can import a library.
02:43
I'm gonna select import and navigate to the three axis
02:46
sample library dot tools that we have with the course.
02:50
Once we select okay notice that now inside of our three access sample library,
02:54
we have a cat 40
03:02
If we expand the cloud library, you can see that three access sample is listed here.
03:06
This sample library only contains this one tool and this holder,
03:10
it's always a good idea that we double check our filters to
03:12
make sure that we don't have any of our filters turned on.
03:15
For example, if you enable milling, you can see that the holder is no longer visible.
03:19
So we want to make sure that any filters
03:21
are cleared and note that we only have our quarter
03:23
end mill and the holder
03:25
in order to create new tools,
03:27
we can either create them from scratch or you can bring them
03:29
in from the fusion 3 60 library or a downloaded vendor library.
03:33
I'm gonna begin by going to the Fusion 3 60 library.
03:37
I'm gonna begin filtering by milling.
03:39
I want to take a look at flat end mills and then I
03:42
want to look for the animals that I need for my specific size.
03:45
In this case we're going to be using a half inch flat and a three quarter flat.
03:50
So as I look through this list, I've got a half inch flat end mill.
03:53
When I select it, notice that there are cutting data presets.
03:57
We have ones for aluminum slotting, roughing and finishing.
04:01
This data is important to review because it doesn't necessarily fit with
04:05
your specific machine or the tool that you're going to use.
04:08
Remember that these are generic tools and their unspecified
04:11
materials and they don't have vendor product links.
04:14
So make sure that you do identify the speeds and
04:17
feeds that you do need to use with these tools.
04:19
But what we're going to do is we're going to
04:21
right click on this tool and select copy tool.
04:25
Go back into our three access sample and we're going to right click and paste
04:29
once again when we do this,
04:31
it's important that we note the filters are going to be active
04:34
and we should clear any filters so we can't see our holder.
04:37
When we take a look at this half inch flat end mill.
04:40
Notice that it doesn't have a tool number
04:43
tool number five is a quarter inch flat end mill.
04:45
Now,
04:46
what we want to do is we want to make sure that
04:47
we edit the properties by right clicking and editing the tool.
04:51
We're going to leave the quarter inch flat end mill as tool number five
04:55
and in the post processor section for our half inch flat end mill.
04:59
We're going to set this at tool number six.
05:02
When we do that,
05:03
the length offset and diameter offset automatically update to six as well.
05:07
It's also important that we take a look at our cutter
05:09
data notice that it's listed as a three flute tool.
05:12
It's going to be using the inch
05:14
unit system and currently the material is unspecified
05:18
if we're using a specific tool such as a car by tool. It's a good idea to specify
05:22
that,
05:23
make sure that the number of flutes is going to match because all
05:26
of these things will affect the overall and use of the tool.
05:30
The diameter is correct at half inch. The overall length at three inch.
05:34
The length below holder is the amount it's sticking out
05:36
below our holder and the shoulder length is one inch.
05:39
This all matches data that we're going to be using
05:42
when we go to the holder section. Notice that by default it's using this cat 40 E. R. 32
05:50
What we can do is we can remove the holder and we can pick a different holder.
05:54
If we have one
05:55
again,
05:56
you can take a look in the three axis samples
05:57
and make sure that you do have the correct holder
05:60
if you want to reassign a holder. What we can do is remove the holder from this,
06:04
we can select and use this holder in its place.
06:07
It's always a good idea to double check the cutting data
06:09
to make sure your length below holder is still the same
06:12
at this point we're going to go ahead and accept this and
06:15
now we've got tool number six are half inch flat end mill.
06:18
We also want to make sure that we have a three quarter flat end mill.
06:21
This is going to be used for us to face and machine the top of our part for this.
06:26
I'm gonna go ahead and hit plus to create a new tool.
06:29
I'm going to select flat end mill and I'm going to
06:32
give it a description of three quarter inch flat end mill
06:37
for the cutter. I'm going to make sure that it is a three flute high speed steel.
06:41
The diameter is going to be 30.75,
06:44
which is going to automatically update the shaft diameter,
06:47
the overall length of three inches, the length below holder of 1.1.
06:51
The shoulder length is going to be one inch and the
06:54
flute length we're going to set as one inch as well
06:58
For the holder. Once again, we want to use that same cap 40.
07:01
It's not strictly required that we are using a holder inside of our tool definition,
07:06
but it is important when we come down to programming our tool paths,
07:10
we want to make sure that the non cutting portion of the tool and
07:13
the holder itself doesn't collide with one machine stock or any of our fixtures.
07:18
I'm gonna set this at tool number four and I'm going to select accept.
07:22
Now we have the tools for our machining or milling applications.
07:26
We want to create the spot drill, the finish drill and the taps as well for that.
07:30
I'm going to go back into my samples.
07:32
I'm going to start looking at whole making category and I want to find a drill bit,
07:37
a spot drill and a tap.
07:38
So I'm going to begin with the spot drill and
07:40
I'm going to find an eighth inch spot drill,
07:42
right click copy tool.
07:44
Go back to my sample, right click and paste the tool.
07:48
Once again,
07:49
the filters are active so you're only going to be seeing the whole making tools.
07:53
Now I want to change from a spot drill to a drill bit.
07:56
We're going to be looking for a 0.201.
07:59
As we scroll down through here,
08:00
we want to make sure that we find the correct
08:02
tool that's going to be used to drill this hole.
08:04
This is the number seven.
08:06
We're going to go ahead and right click and copy this tool and in
08:10
our three access sample we're going to right click and paste the tool.
08:14
The last thing that we are going to need is going to be a right hand tap.
08:18
This is going to be a quarter 20 tap.
08:19
So we want to look through our list, find a quarter 20 tap, right click and copy it.
08:25
Also note that we are able to drag and drop into the three access sample.
08:28
And what that does is it will create a copy of it for us as well.
08:32
This can prevent you from going back and forth
08:34
between the samples and into our current cloud library.
08:38
Once again, make sure that we deactivate the filters.
08:40
We want to assign tool numbers to all these tools,
08:43
I'm going to edit the eighth inch spot drill.
08:46
Go to post process and set this at tool number one.
08:50
We're going to accept that we're going to go to our number seven drill,
08:54
we're going to edit the tool.
08:55
I'm going to set this as tool number two
08:58
and last. I want to go into my quarter 20 tap.
09:02
I'm going to edit the tool and set this as tool number three.
09:06
The tools don't need to be in numerical order.
09:08
They simply need to match however you have them set up inside of your machine.
09:13
It's important to note that the spot drill,
09:15
the drill bit and the quarter 20 tap all have varying levels of detail.
09:20
The tap doesn't contain a holder but the drill and
09:23
the spot drill are using a 40 taper drill chuck.
09:27
So again, it's important to note,
09:28
we want to make sure that these tools can go all the
09:32
way down Down to the bottom of whatever we're machining or drilling.
09:35
Make sure that you validate the speeds and speeds
09:37
that are going to be used in this case.
09:40
Note that in this spot drill,
09:42
the aluminum finishing has a 12,000 rpm
09:45
spindle speed.
09:46
That's going to be too fast for the machine that we're likely going to use.
09:49
And that's something that we would need to adjust.
09:51
This can be done by right clicking and editing the tool.
09:55
We can go to its cutting data,
09:57
make sure that we're on aluminum finishing and we can reduce this value to 8100,
10:02
which should be our limit when we do that.
10:04
It's going to update our surface speed as well as our feed per tooth values.
10:08
The fx next to it is going to tell us that is linked to a parameter
10:12
and those parameters are going to be adjusted
10:15
based on changing just our spindle speed.
10:17
We're going to accept that change and then we're going to close our tool library
10:21
because the tool libraries are saved in the cloud or locally,
10:24
there is no safe option that we need to do.
10:26
Remember that they are independent of our design.
10:29
So the untitled document does not need to be saved
10:32
at this point.
10:33
If you want to make any changes to the tool library,
10:35
go ahead before moving on to the next step
Video transcript
00:02
create and manage a digital tool library.
00:05
After completing this video, you'll be able to create a digital tool library,
00:09
create a custom digital tool,
00:11
copy and modify a digital tool and define tool parameters.
00:18
Infusion 3 60. We're going to get started with a new untitled document.
00:22
We're going to move to the manufacturer workspace.
00:25
And the first thing that I want to do is change the units in this case.
00:28
What we're going to be doing is we're going to be creating a tool library.
00:31
Infusion 3 60. The tool library is going to be independent of any document.
00:35
So changing the units here isn't really needed.
00:38
However,
00:39
it will affect the units that we see displayed
00:41
at the very basic level in our tool library.
00:44
Note that inside of our tool library there's going to be an all section
00:48
will be documents which will be tools that are used in your current document.
00:51
If you have multiple setups,
00:53
you'll also see them listed here underneath your untitled document.
00:57
We have a cloud library, a local library, the fusion 3 60 samples.
01:01
And at the very bottom we can download vendor libraries.
01:04
It's important to note that if you right click on the library,
01:08
you have the ability to turn the libraries on and off.
01:11
This can be done for individual samples.
01:14
For example, if you're not using any of the metric holders,
01:17
you can right click and you can turn this library off.
01:20
This means that it won't be displayed when you're taking a look at the
01:23
various tools and filtering through the different
01:26
holders inside of the sample library.
01:28
If you want to bring it back, you can always right click and turn that library on.
01:32
We're not going to be going through our vendor libraries in this case,
01:35
but I do think that it's important to explore what tools you
01:38
can download from vendor libraries without having to set them up manually.
01:42
Also note that if you don't see cloud listed inside of your tool library,
01:46
make sure that you go to your user preferences and
01:49
we want to make sure that we do enable them
01:51
from the general section you want to go to manufacture
01:53
and make sure that enable cloud libraries is checked.
01:57
Now let's go back into our tool library and let's take
01:60
a look at how we can create our own library.
02:02
All the tools inside of the fusion 3 60 sample library are read only.
02:07
This means that we can take a look at them and we
02:08
can use them in the current document but we can't modify them.
02:12
What we can do is we can create a library in either our local or our cloud location.
02:17
If you happen to log into fusion 360 from multiple computers.
02:20
It's a good idea that you do use the cloud location.
02:23
There are other places in which you can save
02:25
two libraries as well as post processor data by using
02:28
the assets inside of the data panel but we're going
02:31
to focus solely on the cloud and local libraries.
02:34
We're gonna right click and we can either create
02:36
a new empty library that we want to populate.
02:39
We can create a new folder inside of our cloud library or we can import a library.
02:43
I'm gonna select import and navigate to the three axis
02:46
sample library dot tools that we have with the course.
02:50
Once we select okay notice that now inside of our three access sample library,
02:54
we have a cat 40
03:02
If we expand the cloud library, you can see that three access sample is listed here.
03:06
This sample library only contains this one tool and this holder,
03:10
it's always a good idea that we double check our filters to
03:12
make sure that we don't have any of our filters turned on.
03:15
For example, if you enable milling, you can see that the holder is no longer visible.
03:19
So we want to make sure that any filters
03:21
are cleared and note that we only have our quarter
03:23
end mill and the holder
03:25
in order to create new tools,
03:27
we can either create them from scratch or you can bring them
03:29
in from the fusion 3 60 library or a downloaded vendor library.
03:33
I'm gonna begin by going to the Fusion 3 60 library.
03:37
I'm gonna begin filtering by milling.
03:39
I want to take a look at flat end mills and then I
03:42
want to look for the animals that I need for my specific size.
03:45
In this case we're going to be using a half inch flat and a three quarter flat.
03:50
So as I look through this list, I've got a half inch flat end mill.
03:53
When I select it, notice that there are cutting data presets.
03:57
We have ones for aluminum slotting, roughing and finishing.
04:01
This data is important to review because it doesn't necessarily fit with
04:05
your specific machine or the tool that you're going to use.
04:08
Remember that these are generic tools and their unspecified
04:11
materials and they don't have vendor product links.
04:14
So make sure that you do identify the speeds and
04:17
feeds that you do need to use with these tools.
04:19
But what we're going to do is we're going to
04:21
right click on this tool and select copy tool.
04:25
Go back into our three access sample and we're going to right click and paste
04:29
once again when we do this,
04:31
it's important that we note the filters are going to be active
04:34
and we should clear any filters so we can't see our holder.
04:37
When we take a look at this half inch flat end mill.
04:40
Notice that it doesn't have a tool number
04:43
tool number five is a quarter inch flat end mill.
04:45
Now,
04:46
what we want to do is we want to make sure that
04:47
we edit the properties by right clicking and editing the tool.
04:51
We're going to leave the quarter inch flat end mill as tool number five
04:55
and in the post processor section for our half inch flat end mill.
04:59
We're going to set this at tool number six.
05:02
When we do that,
05:03
the length offset and diameter offset automatically update to six as well.
05:07
It's also important that we take a look at our cutter
05:09
data notice that it's listed as a three flute tool.
05:12
It's going to be using the inch
05:14
unit system and currently the material is unspecified
05:18
if we're using a specific tool such as a car by tool. It's a good idea to specify
05:22
that,
05:23
make sure that the number of flutes is going to match because all
05:26
of these things will affect the overall and use of the tool.
05:30
The diameter is correct at half inch. The overall length at three inch.
05:34
The length below holder is the amount it's sticking out
05:36
below our holder and the shoulder length is one inch.
05:39
This all matches data that we're going to be using
05:42
when we go to the holder section. Notice that by default it's using this cat 40 E. R. 32
05:50
What we can do is we can remove the holder and we can pick a different holder.
05:54
If we have one
05:55
again,
05:56
you can take a look in the three axis samples
05:57
and make sure that you do have the correct holder
05:60
if you want to reassign a holder. What we can do is remove the holder from this,
06:04
we can select and use this holder in its place.
06:07
It's always a good idea to double check the cutting data
06:09
to make sure your length below holder is still the same
06:12
at this point we're going to go ahead and accept this and
06:15
now we've got tool number six are half inch flat end mill.
06:18
We also want to make sure that we have a three quarter flat end mill.
06:21
This is going to be used for us to face and machine the top of our part for this.
06:26
I'm gonna go ahead and hit plus to create a new tool.
06:29
I'm going to select flat end mill and I'm going to
06:32
give it a description of three quarter inch flat end mill
06:37
for the cutter. I'm going to make sure that it is a three flute high speed steel.
06:41
The diameter is going to be 30.75,
06:44
which is going to automatically update the shaft diameter,
06:47
the overall length of three inches, the length below holder of 1.1.
06:51
The shoulder length is going to be one inch and the
06:54
flute length we're going to set as one inch as well
06:58
For the holder. Once again, we want to use that same cap 40.
07:01
It's not strictly required that we are using a holder inside of our tool definition,
07:06
but it is important when we come down to programming our tool paths,
07:10
we want to make sure that the non cutting portion of the tool and
07:13
the holder itself doesn't collide with one machine stock or any of our fixtures.
07:18
I'm gonna set this at tool number four and I'm going to select accept.
07:22
Now we have the tools for our machining or milling applications.
07:26
We want to create the spot drill, the finish drill and the taps as well for that.
07:30
I'm going to go back into my samples.
07:32
I'm going to start looking at whole making category and I want to find a drill bit,
07:37
a spot drill and a tap.
07:38
So I'm going to begin with the spot drill and
07:40
I'm going to find an eighth inch spot drill,
07:42
right click copy tool.
07:44
Go back to my sample, right click and paste the tool.
07:48
Once again,
07:49
the filters are active so you're only going to be seeing the whole making tools.
07:53
Now I want to change from a spot drill to a drill bit.
07:56
We're going to be looking for a 0.201.
07:59
As we scroll down through here,
08:00
we want to make sure that we find the correct
08:02
tool that's going to be used to drill this hole.
08:04
This is the number seven.
08:06
We're going to go ahead and right click and copy this tool and in
08:10
our three access sample we're going to right click and paste the tool.
08:14
The last thing that we are going to need is going to be a right hand tap.
08:18
This is going to be a quarter 20 tap.
08:19
So we want to look through our list, find a quarter 20 tap, right click and copy it.
08:25
Also note that we are able to drag and drop into the three access sample.
08:28
And what that does is it will create a copy of it for us as well.
08:32
This can prevent you from going back and forth
08:34
between the samples and into our current cloud library.
08:38
Once again, make sure that we deactivate the filters.
08:40
We want to assign tool numbers to all these tools,
08:43
I'm going to edit the eighth inch spot drill.
08:46
Go to post process and set this at tool number one.
08:50
We're going to accept that we're going to go to our number seven drill,
08:54
we're going to edit the tool.
08:55
I'm going to set this as tool number two
08:58
and last. I want to go into my quarter 20 tap.
09:02
I'm going to edit the tool and set this as tool number three.
09:06
The tools don't need to be in numerical order.
09:08
They simply need to match however you have them set up inside of your machine.
09:13
It's important to note that the spot drill,
09:15
the drill bit and the quarter 20 tap all have varying levels of detail.
09:20
The tap doesn't contain a holder but the drill and
09:23
the spot drill are using a 40 taper drill chuck.
09:27
So again, it's important to note,
09:28
we want to make sure that these tools can go all the
09:32
way down Down to the bottom of whatever we're machining or drilling.
09:35
Make sure that you validate the speeds and speeds
09:37
that are going to be used in this case.
09:40
Note that in this spot drill,
09:42
the aluminum finishing has a 12,000 rpm
09:45
spindle speed.
09:46
That's going to be too fast for the machine that we're likely going to use.
09:49
And that's something that we would need to adjust.
09:51
This can be done by right clicking and editing the tool.
09:55
We can go to its cutting data,
09:57
make sure that we're on aluminum finishing and we can reduce this value to 8100,
10:02
which should be our limit when we do that.
10:04
It's going to update our surface speed as well as our feed per tooth values.
10:08
The fx next to it is going to tell us that is linked to a parameter
10:12
and those parameters are going to be adjusted
10:15
based on changing just our spindle speed.
10:17
We're going to accept that change and then we're going to close our tool library
10:21
because the tool libraries are saved in the cloud or locally,
10:24
there is no safe option that we need to do.
10:26
Remember that they are independent of our design.
10:29
So the untitled document does not need to be saved
10:32
at this point.
10:33
If you want to make any changes to the tool library,
10:35
go ahead before moving on to the next step
After completing this video, you will be able to:
Step-by-step guide
How to buy
Privacy | Do not sell or share my personal information | Cookie preferences | Report noncompliance | Terms of use | Legal | © 2025 Autodesk Inc. All rights reserved
Sign in to start learning
Sign in for unlimited free access to all learning content.Save your progress
Take assessments
Receive personalized recommendations
May we collect and use your data?
Learn more about the Third Party Services we use and our Privacy Statement. May we collect and use your data to tailor your experience?
Explore the benefits of a customized experience by managing your privacy settings for this site or visit our Privacy Statement to learn more about your options.